Depth of cut calculation (for G71 canned cycle)

G0X2.(ADJUST IF NECESSARY)Z1.

(YOU CAN ADJUST #101 AND #102 BUT DO NOT CHANGE ANY OTHER MACRO VALUE BELOW!)

#100=#5001(ADDS CURRENT X-POSITION INTO MACRO) 

#101=2.5(*LONGEST* DIAMETER TO MACHINE IN THE CANNED CYCLE CONTOUR)

 

(ADJUST MAX. DEPTH OF CUT IF NECESSARY) 

#102=.09(MAX. DEPTH OF CUT)


IF[#102GT.25]THEN#3000=100(MAX. DEPTH OF CUT [#102] IS MORE THAN .25" - CHANGE VALUE IN THIS SAFETY LINE IF ARE YOU SURE)

 

(DO NOT CHANGE THE FOLLOWING) 

#103=FUP[[#101-#100]/2/#102] 

(CALCULATED NUMBER OF PASSES)

#104=[[#101-#100]/2/#103+.0001](CALCULATED DEPTH OF CUT +.0001)

#105=[[ROUND[#104*10000]]/10000](ROUNDED DEPTH OF CUT TO BE USED IN FIRST LINE OF CANNED CYCLE)

IF[#103EQ1]THEN#105=#102

G71U#105R.03

G71P.....


Comments

Post a Comment

Popular posts from this blog

List of Macro Variables

Variable Purpose Page #0 Null variable 22 #1 - #33 Local variables 28 #34 - #99 Not available 28 #100 - #199 Common variables 28 #200 - #499 Not available 28 #500 - #999 Permanent common variables (same as common variables, with the difference that the stored values in these are not cleared by reset or power cycle)  28/29 #1000 - #1015 and #1032 Correspond to input interface signals (G54.0 - G54.7, G55.0 - G55.7)  40/41 #1100 - #1115 and #1132 Correspond to output interface signals (F54.0 - F54.7, F55.0 - F55.7) 40/41 #2001 - #2064 X-axis wear offsets (on a lathe with 64 offset numbers) 42 #2001 - #2200 Tool length wear offsets (with parameter 6000#3 = 0, on a milling  machine with 200 offset numbers) 44 #2101 - #2164 Z-axis wear offsets (on a lathe with 64 offset numbers)  42 #2201 - #2264 Nose radius wear offsets (on a lathe with 64 offset numbers) 42 #2201 - #2400 Tool length geometry offsets (with parameter 6000#3 = 0, on a milling machine with 200 offset numbers...
Read more

DN (Doosan) (S)MX error message: return B-axis

Generates an error message and stops the machine in case B-axis has not been returned to clear chuck and tailstock after resetting the machine. For example: Machine has been stopped with a "B0.-tool" like a Mini-turret close to the jaws with tailstock supporting part. If the operator hasn't manually moved the B-axis to min. B-75., machine will stop and the control will display the error message. N100 ( ROUGH TURN ); G40 G80 (NEEDS TO BE CANCELED BEFORE G69.1 ); G69.1; G13.1 ; G28 U0. V0.; IF[#5004 GT-75. ] THEN #3000=100 (MANUALLY MOVE B-AXIS TO WITHIN B-75. TO B-120.); G0 B-90. (NECESSARY TO CLEAR TAILSTOCK); G28 W0.;
Read more

Current machine values

  #504=#5001(ADDS CURRENT X-VALUE INTO MACRO)  #505=#5002(ADDS CURRENT Z-VALUE INTO MACRO)  #500=#4119(ADDS CURRENT SPEED INTO MACRO - IF G96 IS BEING USED, IT'S ACTUALLY THE SPEED LIMIT) #510=#4120(ADDS TOOL NUMBER INTO MACRO) #511=[[FIX[#4120/1000]]*1000](ADDS TOOL CANCEL INTO MACRO)    (#4120 = TOOL-#) #503=#4120-[[FIX[#4120/1000]]*1000](SEPARATE LAST 3 DIGITS) #521=#[15000+[#4120-[[FIX[#4120/1000]]*1000]]](X GEOMETRY OF CURRENT TOOL)  #522=#[16000+[#4120-[[FIX[#4120/1000]]*1000]]](Z GEOMETRY OF CURRENT TOOL)  #523=#[17000+[#4120-[[FIX[#4120/1000]]*1000]]](TOOL RADIUS GEOMETRY OF CURRENT TOOL)  #524=#[10000+[#4120-[[FIX[#4120/1000]]*1000]]](X WEAR OFFSET GEOMETRY OF CURRENT TOOL)  #525=#[11000+[#4120-[[FIX[#4120/1000]]*1000]]](Z WEAR OFFSET GEOMETRY OF CURRENT TOOL)  #526=#[12000+[#4120-[[FIX[#4120/1000]]*1000]]](TOOL RADIUS WEAR OFFSET GEOMETRY OF CURRENT TOOL) 
Read more